The O-Ring Milling Dialog Box
The Machining Method section of the O-Ring dialog box contains the following options.
Roughing
Rough Groove—Remove the material inside the O-Ring feature using rough milling and leaving stock on the Floor according to the Floor Stock value.
Finishing
• Finish Floors—Finish mill the Floor surfaces. When you select this option, you can use the Finish Passes button to set up the number of finish passes and the depth increments.
• Finish Walls—Finish mill the Hard Walls. When you select this option, you can use the Finish Cuts button to set up the number of finish cuts and the depth increments.
• Use CUTCOM—NC output will contain the CUTCOM statements. You can customize their format and locations by clicking the Tool Path Properties button and using the Cut Control tab of the Tool Path Properties dialog box. This option becomes available only when you select the Finish Walls option above.
Cut Motion
These options define where material is relative to the tool rotation:
• Climb—The tool is to the left of material (assuming clockwise spindle rotation).
• Conventional—The tool is to the right of material (assuming clockwise spindle rotation).
Start Position
If the Use Default option is selected, the tool will start at a default position along the closed groove.
If you clear the
Use Default checkbox, you can click
next to it and select a point anywhere on the edges surrounding the closed groove. The tool will start at the position closest to the selected point. Click
to view the start position.
Top Entry
These options describe the way the tool enters the groove:
• Plunge—The tool enters the material vertically.
• Ramp—The tool enters at Ramp Angle to the x-axis of the Program Zero coordinate system. You can customize the Ramp Angle by clicking the Tool Path Properties button and using the Entry/Exit tab of the Tool Path Properties dialog box.
• Entry Hole—The tool enters along a predefined entry hole. To use this option, you must first create and machine an Entry Hole feature.
The Tool Path Properties button opens the Tool Path Properties dialog box, which provides access to lower-level control of the tool path, such as spindle and coolant statements, speeds, feeds, clearances, entry/exit, and cut control options.
The Options section of the O-Ring dialog box contains the following option:
Use Fixture Offset—Allows you to store the fixture transformation offset in a register on your machine. Type the Fixture Offset register value in the text box to the right. If you use this option, NC output will contain the SET/OFSETL statements.